Drill Machine-Dynamic Simulation-Autodesk Inventor 2012 (with caption and audio narration)
Serial No. 30 Drill Machine-Dynamic Simulation-Autodesk Inventor 2012 (with caption and audio narration) In this video, we will demonstrate how to apply the different type of mates in the assembly environment for creating the Dynamic Simulation of the ‘Drill Machine’. Click the following link to get the model file: –http://bit.ly/2ncLp9z Transcription of Video Display of Motion in Drill Machine through Dynamic Simulation Create a New ‘Standard (in).iam’ Assembly and save it with the name ‘Drill Machine-Dynamic Simulation’. Select Place component from the marking menu and place the Frame in the Assembly. Place Handle-1 and Handle Cap-1 in the Assembly. Start the Constrain Command and choose Insert Mate from the type option. First select the inner circular edge of Handle Cap, then select outer circular edge of Handle and click Ok. Give another Insert Mate between Inner edge of Handle Cap and circular edge of Frame as displayed. Re-orient the design window using View Cube. Set the current view as Home View using the toggle next to View Cube. Place Gear Wheel and Gear in the Assembly. Apply a Mate Constraint between Axis of Gear Wheel and Axis of Gear. Next, apply a Mate Constraint between face of Gear Wheel and face of Gear. Apply another Mate Constraint between YZ Plane of Gear Wheel and XZ Plane of Gear. Re-orient the Gear Wheel with respect to Frame using Rotate Component Tool. Apply an Axis Mate between Gear Wheel and stud of Frame. Place Spindle in the Assembly. Apply a Mate Constraint between Axis of Frame and Axis of Spindle. Next, apply a Mate Constraint between inner face of supporting cylinder of frame and back face of the spindle. Place Pinion-2 in the Assembly. Apply a Mate Constraint between Axis of Pinion-2 and Axis of Spindle. Apply an Axis Mate between hole on Pinion-2 and hole on Spindle. Place Locking Pin in the Assembly and fix it inside the hole of Pinion using Insert Mate. Place Pinion-1 in the Assembly. Align the Pinion-1 to match it with the Frame. Apply a Mate Constraint between Axis of Frame and Axis of Pinion-1. Select Pinion-1, Pinion-2 and Gear, then right click in the design window, choose ‘Isolate’ from the context menu. Set the Browser from Assembly view to Modeling View. Locate the Intersection Point of Pinion-2 inside the Browser Bar. Apply a Mate Constraint between the Intersection Point of Pinion-2 and Intersection Point of Gear. In the same manner, apply a Mate Constraint between the Intersection Point of Pinion-2 and the Intersection Point of Pinion-1. Activate Motion Constraint; first select the Axis of Pinion-1 and afterward the Axis of Gear. Enter the value 15/56 in the Ratio Input box and click Apply. Apply same step as above to give motion constraint between Pinion-2 and Gear. Right click in the design window, choose Undo Isolate from the context menu. Place Chuck in the Assembly. Apply a Mate Constraint between the Axis of Spindle and the Axis of Chuck. Place a Mate Constraint between inner circular face of Chuck and front face of Spindle. Place another Mate Constraint between YZ Plane of Chuck and YZ Plane of Spindle. Place Three instances of Jaw in the Assembly. Apply an Axis Mate between two subsequent Jaws. Next, apply a Mate between their edges. Apply a Flush Mate between their end faces. In the same manner, constraint the third Jaw. Apply a Mate Constraint between inner circular face of Chuck and rear face of Jaw. Apply a Mate Constraint between the Axis of Chuck and the Axis of Jaw. Place a Mate Constraint between YZ Plane of Chuck and YZ Plane of any one Jaw. Place Handle-2 and Handle Cap-2 in the Assembly. Apply an Insert Mate between inner circular edge of Handle Cap-2 and outer circular edge of Handle-2. Position the Handle Cap-2 in respect of the stud of Frame by using Rotate Component Tool. Apply an Insert Mate between front circular edge of Handle Cap-2 and inner circular edge of stud. Place Handle Connecting Plate in the Assembly. Apply an Insert Mate between edge of the hole on Handle Connecting Plate and inner circular edge of stud. Place Washer-1 in the Assembly. Apply an Insert Mate between edge of the hole on Washer-1 and edge of the hole on Gear Wheel. Apply a Mate Constraint between YZ Plane of Handle Connecting Plate and Axis of the hole on Gear Wheel. Place Screw-2 in the Assembly. Apply an Insert Mate between inner circular edge of Screw-2 and edge of the hole on Handle Connecting Plate. Place Handle-3 and Handle Cap-3 in the Assembly. Fit the Handle Cap-3 over the Handle-3 with the help of Insert Mate. Apply another Insert Mate between the Handle Cap-3 and hole on the Handle Connecting Plate. Place Screw-1 and Nut in the Assembly. Fix the Screw-1 on the Handle-3 with the help of Insert Mate. Fix the Nut on the Screw-1 by applying Insert Mate. Open the Visibility of surfaces named ‘Pitch Diameter’ of Pinion-2, Pinion-1 and Gear. ‘Isolate’ the Pinion-1, Pinion-2 and Gear in the Assembly. Activate the Dynamic Simulation Tool from the Begin Panel of Environments Tab. Select Insert Joint in the Marking menu. Select ‘Rolling: Cone on Cone’ from the drop down menu of Insert Joint dialog box. Select Pitch Diameter of Pinion-2 in ‘Component 1’ option and select Pitch diameter of Gear in ‘Component 2’ option and click Apply. In the same manner select Pitch Diameter of Pinion-1 and select Pitch diameter of Gear and click Ok. Finish Dynamic Simulation and return to Assembly Modelling environment. Close the visibility of surfaces named ‘Pitch Diameter’ of Pinion-1, Pinion-2 and Gear. Right Click in the design window and click ‘Undo Isolate’ option. Activate Dynamic Simulation Tool. Select Revolution:2 joint in the Browser under the Standard Joints folder, right click and select Properties from the context menu. Click dof 1 (R) tab and select Edit imposed motion button and check the Enable imposed motion option. Click
Vise-Dynamic Simulation-Autodesk Inventor 2012 (with caption and audio narration)
Serial No. 106 Vise-Dynamic Simulation-Autodesk Inventor 2012 (with caption and audio narration) In this video, we will demonstrate how to apply the different type of mates in the assembly environment for creating the Dynamic Simulation of the ‘Vise’. Click the following link to get the model file: – http://bit.ly/2ms77GX Transcription of Video Display of Motion in Vise through Dynamic Simulation Sub Assembly-1: Create a New ‘Standard (in).iam’ Assembly and save it with the name ‘Sub Assembly-1’. Select Place component from the marking menu and place the ‘Base Housing’ in the Assembly. Re-orient the model in the design window by using View Cube. Set the current view as Home View by using the toggle next to View Cube. Place the ‘Part-1’ in the Assembly. Apply a Mate Constraint between the bottom face of Part-1 and inner face of Base Housing. Apply another Mate Constraint between YZ plane of Base Housing and YZ Plane of Part-1. Apply a Flush Mate between front face of Part-1 and front face of Base Housing. Fill the offset value 5.672 inch. Place the ‘Jaw Plate’ in the assembly. Apply a Mate Constraint between slotted face of Base Housing and back face of Jaw Plate. Next apply a Mate Constraint between lower face of slotted face and bottom Face of Jaw Plate. Apply a Flush Mate between the side face of Jaw Plate and side face of Base Housing. Place two identical ‘Screws’ in the Assembly. Fix both the Screws in the holes on Jaw Plate by using the Insert Mate. Save the Sub Assembly-1 and close it. Sub Assembly-2: Create a New Assembly and save it with the name ‘Sub Assembly-2’. Select Place component from the marking menu and place the ‘Sliding Housing’ in the Assembly. Re-orient the model in the design window by using View Cube. Set the current view as Home View by using the toggle next to View Cube. Place the ‘Jaw Plate’ in the Assembly. Apply a Mate Constraint between slotted face of Sliding Housing and back face of Jaw Plate. Next apply a Mate Constraint between lower face of slotted face and bottom Face of Jaw Plate. Apply a Flush Mate between the side face of Jaw Plate and side face of Sliding Housing. Place two identical ‘Screws’ in the Assembly. Fix both the Screws in the holes on Jaw Plate by using the Insert Mate. Save the Sub Assembly-2 and close it. Sub Assembly-3: Create a New Assembly and save it with the name ‘Sub Assembly-3’. Select Place component from the marking menu and place the ‘Threaded Spindle’ in the Assembly. Place the ‘Compress Spring’ in the Assembly. Apply a Mate Constraint between Y Axis of Compress Spring and Axis of Threaded Spindle. Apply a Mate Constraint between circular face of Threaded Spindle and face of Compress Spring. Place the ‘Washer’ in the Assembly. Apply an Axis Mate between Washer and Threaded Spindle. Apply a Mate Constraint between face of Washer and face of Compress Spring. Place the ‘Pin’ in the Assembly. Apply an Axis Mate between Pin and hole on the Threaded Spindle. Apply a Mate Constraint between XY Plane of Threaded Spindle and YZ Plane of Pin. Place the ‘Handle’ in the Assembly. Apply an Axis Mate between hole on the Threaded Spindle and Handle. Next apply a Mate Constraint between XZ plane of Threaded Spindle and YZ Plane of Handle. Save the Sub Assembly-3 and close it. Main Assembly (Vise): Create a New Assembly and save it with the name ‘Vise-Dynamic Simulation’. Select Place component from the marking menu and place the ‘Sub Assembly-1’ in the Assembly. Re-orient the model in the design window by using View Cube. Set the current view as Home View by using the toggle next to View Cube. Place ‘Sub Assembly-2’ in the Assembly. Align the Sub Assembly-2 in front of Sub Assembly-1 by using Rotate Component Tool. Apply a Mate Constraint between the bed of Sub Assembly-1 and bottom face of Sub Assembly-2. Apply a Flush Mate between YZ Plane of Sub Assembly-1 and XY Plane of Sub Assembly-2. Place ‘Sub Assembly-3’ in the Assembly. Apply an Axis Mate between hole on the Sliding Housing and Threaded Spindle. Apply a Mate Constraint between outer rim of hole on Sliding Housing and rear face of Threaded Spindle. Apply a Mate Constraint between subsequent faces of Jaw in the Assembly. Select the previous applied ‘Mate:4’under the Sub Assembly-1 in the Browser Bar, Right click and choose ‘Supress’ from the context menu. Dynamic Simulation Activate the Dynamic Simulation Tool from the Begin Panel of Environments Tab. Select Insert Joint in the Marking menu. Select ‘Screw’ from the drop down menu of Insert Joint dialog box. In the Insert Joint dialog box, select Circular edge of Threaded Spindle in ‘Component 1’ selection option and select Circular edge of Part-1 in ‘Component 2’ selection option. Enter the value 1/7 in the ‘Pitch’ input box. Click OK. Select Revolution:2 joint in the Browser under the Standard Joints folder, right click and select Properties from the context menu. Click dof 1 (R) tab and select Edit imposed motion button and check the Enable imposed motion option. Click the arrow to expand the input choices, and click Constant Value. Enter the value -360*7 deg/s and click OK. In Simulation Player, fill the value 1000 in the Images field area. Clear the screen by activating the Clean Screen command. Click Run in the Simulation Player to display motion in Vise. Change the colour of Vise ‘Green (Clear)’ to watch its motion in transparent view.
