Animation displayed in ‘Drill Machine’ Assembly–SolidWorks 2014 (with caption and audio narration)
Serial No. 219 Animation displayed in ‘Drill Machine’ Assembly–SolidWorks 2014 (with caption and audio narration) In this video, we will demonstrate how to apply the different type of mates in the assembly environment for creating the animation. ……………………………………………………………………….To watch full sketching video of this model ‘Drill Machine’, please visit my another associated video named as ‘Drill Machine’ (Video Tutorial) SolidWorks. Click the following link to get the model file: – http://bit.ly/2LMF9zg Transcription of the Video Create a new assembly within an English template. The ‘Begin Assembly’ command is preactivated in the assembly design window. Go to the View tab, turn on the ‘Origins’ button. Place the ‘Drill Machine Frame’ in the assembly. Turn off the visibility of ‘Origins’ button. Save the file, call it as ‘Drill Machine with Animation’. Right-click on the design window and choose ‘New View’ tool in the Orientation dialogue box. Save the view as ‘Custom View’ in the Named View dialogue box and click OK. Activate the ‘Insert Components’ command and place the ‘Part9’ & ‘Part10’ file in the assembly. Rotate the ‘Part9’ file to the proper position by using ‘Move with Triad’ command. Apply a ‘Concentric’ mate between the selected inner cylindrical face of ‘Part9’ and outer cylindrical face of ‘Part10’. Choose ‘Lock Rotation’ option to stop the movement of the part, click OK to execute the command. Drag the ‘Part9’ file and apply ‘Coincident’ mate between the selected face of ‘Part10’ and selected inner circular face of ‘Part9’. Apply a ‘Concentric’ mate between the hole of ‘Part10’ and selected cylindrical face of ‘Drill Machine Frame’, which is highlighted in blue color. Choose ‘Lock Rotation’ option and click OK. Apply a ‘Coincident’ mate between the selected face of ‘Part9’ and selected face of ‘Drill Machine Frame’. Place the ‘Spindle’ in the assembly. Rotate the ‘Spindle’ in a proper position by using ‘Move with Triad’ command. Apply a ‘Concentric’ mate between the cylindrical face of ‘Spindle’ and the selected face of the hole of ‘Drill Machine Frame’. Drag the ‘Spindle’ and apply ‘Coincident’ mate between the selected face of ‘Spindle’ and selected face of ‘Drill Machine Frame’. Place the ‘Partr1’ file in the assembly. Apply a ‘Concentric’ mate between the cylindrical face of ‘Part1’ and cylindrical face of ‘Spindle’. Apply a ‘Coincident’ mate between the selected face of ‘Spindle’ and inner circular face of ‘Part1’. Apply another ‘Coincident’ mate between the Top Plane of ‘Spindle’ and Front Plane of ‘Part1’. Drag the chuck of a drill, you can observe here it is moving with the spindle. Save the assembly. Place the ‘Part2’ file in the assembly. Select the ‘Part2’ file from the Model Tree and drag two more copies of ‘Part2’ in the design window. Go to the View tab, turn on the ‘Temporary Axes’ button. The centre axis is visible in the assembly design window. Select the three copies of ‘Part2’ and rotate it. Apply a ‘Coincident’ mate between the ‘Axis1’ of first copy of ‘Part2’ and ‘Axis1’ of second copy of ‘Part2’. Next, apply a ‘Coincident’ mate between their slant edges. In the same way, apply a ‘Coincident’ mate between the second copy of ‘Part2’ and third copy of ‘Part2’. At the last, apply a ‘Coincident’ mate between their selected faces of ‘Part2’ files. Select all the components and rotate it. Apply a ‘Coincident’ mate between the Axis1 of ‘Part2’ and centre axis of the assembly. Apply a ‘Coincident’ mate between the inside circular face of ‘Part1’ and selected face of ‘Part2’. Turn off the ‘Temporary Axes’ button. Drag the ‘Part2’ file to examine the mate. Now see, the ‘Part2’ is moving on its own axis, so we will attach the planes of ‘Part1’ & ‘Part2’ by using ‘Coincident’ mate command. Select the Right Plane of ‘Part2’ and Front Plane of ‘Part1’ and activate the ‘Mate’ command. Click OK to execute the command. Now drag the ‘Part1’ to see the result. ‘Part1’, ‘Part2’ & Spindle of drill machine, each are rotating simultaneously. Save the assembly. Place the ‘Pinion-1’ in the assembly. Rotate the ‘Pinion-1’ in a suitable position by using ‘Move with Triad’ command. Apply a ‘Concentric’ mate between the center hole of ‘Pinion-1’ and selected cylindrical face of ‘Drill Machine Frame’. Place the ‘Pinion-2’ in the assembly. Apply another ‘Concentric’ mate between the center hole of ‘Pinion-2’ and cylindrical face of ‘Spindle. Apply a ‘Concentric’ mate between the side hole of the ‘Pinion-2’ and hole of ‘Spindle’. Place the ‘Revit’ in the assembly and fix it with the ‘Pinion’ by using ‘Mate’ command. Now drag the Pinion to examine the result. Place the ‘Bevel Gear’ & ‘Part7’ in the assembly. Rotate the ‘Bevel Gear’ & ‘Part7’ models in a desired position by using ‘Move with Triad’ command. Apply a ‘Concentric’ mate between the inner cylindrical face of ‘Bevel Gear’ & outer cylindrical face of ‘Part7’. Choose ‘Lock Rotation’ option and click OK to finish the command. Apply a ‘Coincident’ mate between the selected face of ‘Part7’ & selected face of ‘Bevel Gear’. Apply a ‘Concentric’ mate between the hole of ‘Part7’ & selected cylindrical face of ‘Drill Machine Frame’. Select the ‘Pinion-1’ & ‘Pinion-2’ from the model tree, right-click and choose ‘Isolate’ option. Go to the View tab, switch on the ‘Points’ button. The two points of ‘Pinion-1’ & ‘Pinion-2’ are visible in the design window. Whose names are ‘Intersection’ points, these points are also called as Vertices. Drag the Pinion-1 and activate the ‘Mate’ command, select intersection points of ‘Pinion-2’ & ‘Pinion-1’. And apply a ‘Coincident’ mate, disable the ‘Exit Isolate’ button. Drag the ‘Part7’ and switch-on the ‘Temporary Axes’ button. Apply a ‘Coincident’ mate between the Intersection point of ‘Bevel Gear’ and center axis of the assembly. Switch-off the ‘Points’ & ‘Temporary Axes’ button. Select the ‘Pinion-1’, ‘Pinion-2’ & ‘Bevel Gear’ part files from the model tree, right-click and choose ‘Isolate’ option. Activate the ‘Mate’ command, go to the ‘Mechanical Mates’ tab in the Mate dialogue box. Different types of mechanical mates are available here, choose any mate as
